Contact Us
  • Home
  • BLOG
  • How Many Thermal Vias Does a Power Package Need?

How Many Thermal Vias Does a Power Package Need?

Count the heat path in degrees per watt, not the vias. A 0.3 mm plated via through a 1.6 mm board is worth about 190 C/W on its own; a 5 by 5 array of the same via on 0.6 mm pitch measures around 20 to 30 C/W; and once the array is better than the spreading resistance of the copper pad sitting on top of it, more vias change nothing. A 3 W part allowed a 50 C rise needs 16 C/W, and that is a 25 to 30 via array under the exposed pad, not the four vias that usually get drawn.

Where the single via number comes from

A plated through hole is a copper cylinder and it can be treated as one. A 0.3 mm drill with 25 micrometres of plating leaves a copper wall of 0.0216 square millimetres. Thermal resistance is length divided by conductivity times area: 1.6 mm over 385 W/mK times 0.0216 mm2 gives 190 K/W. That is arithmetic, not a rule of thumb, and it is the only number a thermal calculation needs to start from.

Filling the barrel changes it. Solder conducts at about 50 W/mK, far below copper, but the solder core fills the whole 0.25 mm inner diameter and works in parallel with the wall. The same via drops to roughly 145 K/W, about a quarter better than an air filled barrel. That is IPC-4761 Type VII, filled and capped, and it is the only version worth putting inside a thermal pad, because an open barrel also traps flux and outgasses at reflow.

Then the array. Twenty five vias at 190 K/W in parallel should read 7.6 K/W and they never do, because each via only taps the copper within a millimetre or two of itself and heat has to travel sideways through 35 micrometre copper to reach the next one. Measured arrays land at 20 to 30 K/W, and that factor of three is why a calculation done on pure parallel resistance overstates the board and the first build runs hot.

Unless the board is a heavy copper build. At 4 oz outer copper the spreading resistance collapses and the array gets closer to the parallel figure, which is why a 4 oz board can run fewer vias for the same junction temperature. That is a real lever, and it belongs in the stack discussion rather than in a note on the assembly drawing.

What sets the count in practice

The watts and the allowed rise. Work backwards from junction temperature: package theta JC, the pad, the vias, the internal planes, the heatsink interface and the ambient. Whatever is left over is the budget for the board.

The pad area. A 5 by 5 mm exposed pad takes 25 vias on 0.8 mm pitch and no more. Vias on 0.6 mm pitch give 49 in the same area, but each one is closer to its neighbour than to the heat source, so the count is capped by the copper, not by the drill.

Via to pad edge. Keep 0.3 mm of copper between the via barrel and the pad edge where the via sits outside the pad. Under a mask defined pad that distance is what stops the mask shelf from cracking at the first thermal cycle.

Void in the joint. A thermal pad with 20 percent void by area loses the equivalent of a third of its vias. The usual acceptance is under 5 percent by area on the thermal pad, and it has to be measured with CT rather than with a 2D X-ray that cannot see where the void sits in the thickness.

The interface above. A heatsink with a 50 to 100 micrometre thermal interface layer and a flat board is part of the same path. A board at the 0.75 percent warpage limit on a 200 mm span is 1.5 mm out of flat, and no interface material fills that gap.

Three ways the array stops working

Vias pushed outside the pad onto the ground pour. It looks tidier and it costs most of the benefit. A via 3 mm from the pad centre is worth roughly a third of a via under the pad, because the heat has to cross 3 mm of 35 micrometre copper first. On a 3 W part that is the difference between a 45 C rise and a 90 C rise.

Tented vias, IPC-4761 Type I, under a thermal pad. The barrel is left open and covered with mask, so it holds air. Air conducts at 0.026 W/mK, which is three orders of magnitude below the plating, and the flux inside boils at reflow and blows a void in the joint directly above it. The via is then a mechanical feature and not a thermal one.

Thermal relief spokes on the pad connection. Two or four 0.3 mm spokes carry less than one via and they are placed exactly where the current and the heat want to leave. Use a solid connection into the plane and let the array do the work, and keep the reliefs for hand soldered through hole parts.

What SUPERB PCB and SUPERB Assembly support

Filled and capped vias to IPC-4761 Type VII with a dimple of 10 micrometres or less, laser drilling from 0.075 mm and mechanical drilling from 0.15 mm, plating of 20 micrometres or more, outer copper to 10 oz and inner copper to 6 oz, 1 to 20 layers on the standard FR-4 line and up to 68 layers on the high layer count line, and warpage held to 0.75 percent for SMT and 0.5 percent on HDI and rigid flex.

On the assembly side the pad is printed with 3D SPI before reflow, reflowed on a 12 zone profile with nitrogen below 500 ppm on SAC305, and checked with 2D and CT X-ray to IPC-7095 where the void figure matters. Where a heatsink is part of the build, the flatness and the interface thickness are checked before the screws go in, because a warped board with a bolted heatsink craters the pad instead of cooling it. The fine pitch window is on HDI fabrication, the overall route on PCB capability, and the assembly flow on turnkey PCBA assembly.

One honest limit: the thermal resistance of an array is a measured property of the whole stack, not of the vias. If the junction temperature has to be guaranteed, the number comes from a thermal test board or from the package vendor model, and what we supply is the copper, the fill, the voids and the flatness that the model assumes.

What to send

Send the package and the exposed pad dimensions, the power dissipation, the allowed junction and ambient temperature, the stack with copper weights, the heatsink and interface material if there is one, and whether the vias must be filled. That is enough to fix the count, the pitch and the fill before the first panel is drilled.

Need a quote or a review of your files against these criteria? pcba@superb-tech.com · WhatsApp +86 133 9608 1443