If the via sits inside a pad that has to be soldered, the type you want is Type VII: filled, planarised and capped with copper, so the finished surface is a flat solderable pad. If the via has to be flat but nobody will solder to it, Type V, filled and planarised without a copper cap, is enough. If the only goal is to stop paste wicking into the barrel and protect the hole, Type III or IV, plugged and optionally covered by solder mask, is the economical answer. Types I and II, tented by mask, do not belong inside a pad at all.
Most arguments about via in pad are about a fabrication note that says "via in pad" and nothing else. The shop applies its own default, and the default is rarely the one the assembly house needs.
The seven types and what each one actually gives you
| Type | Protection | What it is good for | Where it fails |
|---|---|---|---|
| I | Tented | Vias away from pads, cheap protection of the barrel | Mask tents over a hole; paste still pulls into the barrel if it is in a pad |
| II | Tented and covered | Same as I, with mask on both sides | Same limitation, plus mask blistering over a large hole |
| III | Plugged | Stops paste and flux entering the barrel, keeps the hole out of the reflow path | Plug material is not planar; a dimple remains |
| IV | Plugged and covered | Plugged, then mask over the plug | Mask over a soft plug can lift during reflow or cleaning |
| V | Filled | Flat surface for a via that must not disturb anything placed over it | Fill material is not a solderable finish; solder does not wet to it properly | Filled and covered | Flat, then mask over the fill | Not solderable, so not usable as a pad |
| VII | Filled and capped | Flat, copper capped, solderable: the thermal or ground pad under a QFN or BGA | Extra process steps, so the most expensive type per panel |
The table is a map, not a substitute for the standard. IPC-4761 names these types, and the fabrication note on the purchase order is what settles an argument, so the type number belongs there in writing.
Why an unfilled via in a pad fails at reflow
The arithmetic explains most of it. Take a 0.5 mm square pad, a 0.10 mm stencil and a 0.2 mm finished via through a 1.6 mm board. The paste deposit is 0.025 cubic millimetres. The barrel has a volume of about 0.05 cubic millimetres, twice the paste. Nothing else has to go wrong for the joint to starve: the paste flows into the hole, the pad is left with a thin collar, and the part sits down on a joint that looks closed under AOI because the fillet is hidden.
The second mechanism is outgassing. A plugged or filled via carries a polymer into a barrel that sees 240 degrees or more several times. If the fill is not fully cured, the material vents during reflow and blows a void into the joint from below, which shows on X-ray as a round void in the middle of the thermal pad and looks exactly like a paste problem.
The third is wicking during through hole assembly. On a mixed board, a via in pad that is not protected pulls solder away from a pin in the same net, and the pin ends up with an incomplete fillet on the top side.
Four things that go wrong with the callout
Leaving the type to the shop. "Via in pad, filled" without a type number is read as Type V by one supplier and Type VII by another, and the difference shows up as an unsolderable thermal pad or as a pad with a dimple that traps flux. Write the type, the fill material class, and the maximum dimple on the note.
Specifying Type VII where Type V or IV would do. Filling and capping adds drill and fill cycles, planarising and extra plating. On a board with 2,000 vias in pads, applying the top type across the whole board rather than where solder actually lands is one of the fastest ways to double a fabrication price without improving yield.
Assuming a laser microvia behaves like a mechanical via. A 0.1 mm laser via in an HDI build is filled and capped as part of the build-up, with its own dimple and its own plating; a 0.3 mm mechanical via in the same panel needs a different fill and a different cure. Stacked microvia structures add a further constraint, because the fill sits between layers that are pressed again.
Qualifying the dimple from a single cross-section. Fill shrinks, and it shrinks differently at the panel edge than in the middle, so a first article cross-section taken from the centre can pass while the panel perimeter sits outside the limit. The measurement has to be a surface measurement, on several positions per panel, after planarising and after the cap plating.
What to put on the fabrication note
Five lines cover it: the type number per via class, the fill material (non conductive is normal, conductive only for a current path), the maximum dimple, whether the cap is plated over or mask covered, and the inspection method the shop has to report. A dimple limit of 25 micrometres is a common starting point, and pad pitches below 0.4 mm usually justify something tighter.
How SUPERB handles via in pad
SUPERB PCB runs HDI builds to 30 layers any layer, with 0.035 mm line and space, and applies via fill with vacuum plugging, planarising and cap plating where a pad has to remain solderable. Filled and capped vias are checked by surface measurement per panel plus cross-section at first article, and by X-ray and CT on the assembly side once the part is placed. Mixed technology panels combine HDI, heavy copper and back drilled areas, with 50 ohm impedance held to plus or minus 5 percent and to plus or minus 2 percent on critical runs. Capacity is 2.05 million square feet a month and panels go to 622 by 1092 mm.
Assembly is where the type finally proves itself. SUPERB Assembly runs seven SMT lines with 3D SPI before reflow, 3D AOI after, twelve zone nitrogen reflow below 500 ppm oxygen, and X-ray and CT to IPC-7095 for bottom termination components, with rework held to IPC-7711 and IPC-7721. Systems are certified to ISO 9001, with ISO 13485 for medical work, and components carry a 730 day warranty.
Start from the HDI PCB capability page or the PCB capability summary, and send the stack-up with the pad and via table. A reply will state which vias need Type VII, which can stay at Type IV, and what the dimple limit should be for the pitch you are using.